Carrier board design guidelines (SOM)

Info Box Applies to Naon Applies to Maya Applies to Lizard Applies to Diva

The information here provided are preliminary and subject to change.

Introduction

This page provides useful information and resources to system designers in order to design carrier boards hosting DAVE system-on-modules (SOM).

These guidelines are provided with the goal to help designers to design compliant systems with DAVE modules and they cover schematics and PCB aspects. They apply to several products that are listed on the top right corner of this page (see "Applies to" boxes).

Basics Guidelines

In this section basics hardware guidelines valid for all DAVE SOMs are analyzed.

Schematics

• Check mirroring and pinout of DAVE system-on-modules (SOM) connector
• Properly decouple DAVE system-on-modules (SOM) power supply with large bulk capacitor and small bypass capacitor
• Use low-ESR X7R capacitor if possible
• Check for correct connection of TX and RX lines
• Add series resistors as interface needs (see interface details)

PCB

PCB Tecnology

Use a PCB technology as advised in the following table

Parameter	Min	Typ	Max
Layers(number)	4	6	-
Power Plane Layers	2	4	-
Clearence(mils)	-	6	-
Vias hole (mechanical)	0,3		-
Minimum number of via for each power signal layer changes	2	3	-
Minimum number of via for each power signal SOM connector pin	1	2	-
Component package size	-	0603	-
PCB Height(mm)	1,4	1,6	-

• If vias smaller than minimum advised size are used, take care to maintain an adeguate number of via when you change layer for each power signal.
  
• PCB heights less than minimum advised can produce PCB heating and mechanical issues

PCB Basics Guidelins

• Avoid stubs
• Isolate clock and HI-SPEED signal (see interface specifications for further details)
• Avoid voids on planes
• Use Solid Connection for on plane vias
• Place bulk and ByPass capacitor near DAVE system-on-modules (SOM) power supply pins

Interfaces Guidelines

This section provides guidelines for the most used interfaces on DAVE's SOMs module.
Please refer to SOM's detailed pages for specific additional information.

Ethernet 10/100

Case #1: PHY is integrated on SOM

This section refers to the case of PHY integrated on SOM such as Lizard and Maya.

Schematics

• If LAN connector with integrated magnetic is used:
  • predispose some protection diodes on ethernet lines
  • Connect connector shield to an adeguate GND or shield Plane

PCB

Parameter	Min	Typ	Max
Differential Impedance(ohm)	-	100	-
Common Mode Impedance	-	50	-
Gap than TX and RX signals	2xgap	2xgap	-
Gap than other signals	2xgap	4xgap	-
Intra pair matching(mils)	0	25	240
TX and RX via mismatch	0	0	1
Max PCB trace length	-	-	3"

• If LAN connector with integrated magnetic is used:
  • do not route traces under the connettor, neither on opposite side
  • place filter diode near connector
  • place others signals far from connector
  • Connect connector shield to an adeguate GND or shield Plane or Copper through numerous vias
• If on board magnetic are used
  • adeguately isolate system GND from magnetic connector side
  • Connect connector shield to an adeguate GND or shield Plane or Copper through numerous vias if necessary
• try to match as best as possible each differential pair (intrapair matching)
• Keep as best as possibile the same route for TX and RX traces
• If less than minimum gap is used, use a GND trace for improve trace separation

Case #2: PHY is not integrated on SOM and a RGMII PHY is used

This section refers to the case of PHY is not integrated on SOM and a RGMII Gigabit Ethernet PHY is used such as Naon.

Schematics

• Add series resistors (RPACK resistors recommended) to RGMII lines
• Properly decouple PHY Power Supplies rails
• Properly decouple every supply pin of Ethernet PHY
• Properly separate analog Supply Rails

PCB

Parameter for RGMII interface	Min	Typ	Max
Common mode impedance(ohm)	-	50	-
Gap than other ethernet diff pair	4xwidth	-	-
Gap than other signals	4xwidth		-
Matching(mils)	-	250	-
Via Mismatch	0	0	1

Parameter for Gigabit Differential Pairs	Min	Typ	Max
Differential Impedance(ohm)	-	100	-
Common Mode Impedance	-	50	-
Gap than TX and RX signals	2xgap	2xgap	-
Gap than other signals	2xgap	4xgap	-
Intra pair matching(mils)	0	10	10
TX and RX via mismatch	0	0	1
Max PCB trace length	-	-	3"

• Ground and VCC planes must be as large as possible
• Avoid plane split and voids
• Place bypass capacitor near every PHY supply pin
• Connect every capacitor's pin to the plane with at least 2 vias and the shortest trace pattern
• Place PHY device at least 1" (25mm) distance far away from connector
• Keep MDIO clock signal isolated from other signals

Case #3: PHY is not integrated on SOM and a RMII PHY is used

This section refers to the case of PHY is not integrated on SOM and an RMII 10/100 Ethernet PHY is used such as Maya.

Schematics

• If possible, place series resistor to RMII interface signals
• Properly decouple PHY Power Supplies rails
• Properly separate analog Supply Rails
• Properly decouple every supply pin of Ethernet PHY
• Use a standard RMII PHY that supports correct clock mode (see SOM specification for further details)

PCB

Parameter for RMII interface	Min	Typ	Max
Reccomended Common mode impedance(ohm)	-	50	-
Gap between other signal	2xW		-

• Since RMII signals are not critical such as RGMII, is not necessary a strong matching between signal
• Avoid use of long traces
• Avoid stubs
• Keep as best as possibile the same routing for all RMII traces

Parameter for Ethernet Differential Pairs	Min	Typ	Max
Differential Impedance(ohm)	-	100	-
Common Mode Impedance	-	50	-
Gap than other TX and RX signals	2xgap	2xgap	-
Gap than other signals	2xgap	4xgap	-
Intra pair matching(mils)	0	25	150

• Ground and VCC planes must be as large as possible
• Avoid plane split and voids
• Place bypass capacitor near every PHY supply pin
• Connect every capacitor's pin to the plane with at least 2 vias and the shortest trace pattern
• Place PHY device at least 1" (25mm) distance far away connector
• Keep MDIO clock signal isolated from other signals

USB

Schematics

• Create schematic in accordition with DAVE system-on-modules (SOM) USB specification ( see SOM detailed pages )

PCB

Parameter for USB Differential Pairs	Min	Typ	Max
Differential Impedance(ohm)	80	90	100
Common Mode Impedance	40,5	45	49.5
Gap than other signals	3xgap	5xgap	-
Intra pair matching(mils)	0	25	150
Max allowed stubs	-	-	0
Max traces length	-	-	note 1
Max allowed plane split under traces	-	-	0

note 1 see SOM detailed specifications

• If a stub is unavoidable in the design, no stub should be greater than 200 mils.
• Place a continuos reference plane underneath differential pair

HDMI

Schematics

• Add a Transmitter Port Protection to HDMI lines
• Use certified HDMI connector
• Connector shield must be properly connected

PCB

Parameter for HDMI Differential Pairs	Min	Typ	Max
Differential Impedance(ohm)	85	100	115
Gap than other signals	3xgap	5xgap	-
Intra pair matching(mils) at 225MHz clock	0	80	250
Inter pair matching(mils) at 225MHz clock	0	250	1"
Max allowed stubs	-	-	0
Max allowed plane split under traces	-	-	0

• Place a continuos reference plane underneath differential pair

SATA

Schematics

• Use certified SATA connector

PCB

Parameter for SATA Differential Pairs	Min	Typ	Max
Differential Impedance(ohm)	80	100	120
Common Mode Impedance(ohm)	51	60	69
Gap than other signals	2xgap	-	-
Intra pair matching(mils	0	15	25
Inter pair matching(mils)	0	15	25
Max allowed stubs	-	-	0
Max allowed plane split under traces	-	-	0
Max allowed length	-	-	note 1

note 1 see SOM detailed specifications

• Place a continuos reference plane underneath differential pair
• Minimized vias use

LCD Interface

Schematics

• Please refer to DAVE system-on-modules (SOM) specific documentation
• Predispose series resistor terminator (RPACK for LCD data and single resistor for Clock and H-SYNC and V-SYNC)

PCB

• If possible, use 50ohm common mode lines
• Match LCD parallel signals in accordition with Pixel Clock frequency (further details in SOM specifications)

VIN Interface

Schematics

• Please refer to DAVE system-on-modules (SOM) specific documentation
• Predispose series resistor terminator (RPACK for LCD data and single resistor for Clock and H-SYNC and V-SYNC)

PCB

• If possible, use 50ohm common mode lines
• Match VIN parallel signals in accordition with Pixel Clock frequency (further details in SOM specifications)

TVOUT

Schematics

• Please refer to DAVE system-on-modules (SOM) specific documentation

PCB

Parameter for SATA Differential Pairs	Min	Typ	Max
Common Mode Impedance(ohm)	-	75	-
Gap than other signals	2xwidth	-	-

I2C Interface

Schematics

• Please refer to DAVE system-on-modules (SOM) specific documentation
• Predispose properly pullup resistors on line in accordition with DAVE system-on-modules (SOM)
• Do not overload I2C lines with too much devices
• Ensure that I2C devices are properly reset during power up

PCB

• Isolate I2C clock from noise senitive signals
• Avoid stub